PP Tables and PP Word Syntaxes
PP Word Tables
You can create and manage Post-Processor word tables with NC Manufacturing
products.
Sample PP word tables are delivered with the product in the ..\startup\manufacturing\PPTables
folder. Each PP word table is stored in a unique text file with suffix
pptable. These tables can be used as a basis for creating user-defined
tables.
A PP word table can be defined for a specific machine tool and used in
NC applications.
You can also define the general syntaxes of post-processor words. These
syntaxes will be proposed when you want to create a PP instruction.
A PP word table comprises:
- major words without parameters
- major words with a text
- major words with parameters
- minor words
- word syntaxes.
You can define for a given machine tool:
The NC Manufacturing product will resolve the parameters of these syntaxes
and syntax sequences and generate the corresponding statements in the APT
output.
Note:
TPRINT and NOTE are automatically included in the lists of major words with
parameters and minor words respectively even if they are not specifically
declared in the PP word table.
NC Commands
You can define for a given machine tool (i.e. post-processor) PP word
syntaxes associated to particular NC commands.
An NC command is a machine function such as feedrate declaration (NC_FEEDRATE)
or spindle activation (NC_SPINDLE_START).
A syntax comprises a major word and one or more syntax elements such
as minor words, numerical values, lists and parameters.
A syntax that includes lists or parameters is a parameterized syntax
(see example below):
*START_NC_COMMAND NC_COMPENSATION
LOADTL/%MFG_TL_NUMBER,%MFG_TOOL_COMP
*END
Note that the & character indicates a list and the % character
indicates a parameter. A list has a finite number of values. You can define
only one syntax for each NC command.
The example below shows how lists can be used to define inch units
for feeds and speeds:
*START_NC_COMMAND
NC_FEEDRATE
*START_LIST MFG_FEED_UNIT
IPM ,IPR
*END
FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
*END
/
*START_NC_COMMAND
NC_SPINDLE_START
*START_LIST MFG_SPNDL_UNIT
RPM ,SFM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
*END
/
*START_NC_COMMAND
NC_SPINDLE_LATHE
*START_LIST MFG_SPNDL_UNIT
RPM ,SFM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
*END
The example below shows how lists can be used to define metric units
for feeds and speeds:
*START_NC_COMMAND
NC_FEEDRATE
*START_LIST MFG_FEED_UNIT
MMPM ,MMPR
*END
FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
*END
/
*START_NC_COMMAND
NC_SPINDLE_START
*START_LIST MFG_SPNDL_UNIT
RPM ,SMM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
*END
/
*START_NC_COMMAND
NC_SPINDLE_LATHE
*START_LIST MFG_SPNDL_UNIT
RPM ,SMM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
*END
For an example of how to define syntaxes in NC commands, please see
PP Word Syntaxes in the Customizing section
of this guide.
Arithmetic Operators
It is possible to use the following arithmetic operators in PP word syntaxes:
- addition (+)
- subtraction (-)
- multiplication (*)
- division (/).
These operators can be used:
- between word syntaxes (for example, %MFG_xxx + %MFG_yyy)
- between a value and a word syntax (for example, n + %MFG_yyy)
- between a word syntax and a value (for example, %MFG_xxx + n)
- between values (for example, n + m).
Parenthesis are not needed in expressions except for design parameters,
such as (syntax %(AB)), created using Knowledgeware capabilities.
Operators are processed in the order they appear in the syntax. For example:
%MFG_xxx + %MFG_yyy * %MFG_zzz
This means that %MFG_xxx is added to %MFG_yyy, then this sum is multiplied
by %MFG_zzz.
You should avoid using the +, -, *, / characters for other meanings.
For example, you could use an underscore (_) instead of a dash (-) in the
following expression to avoid any ambiguity:
PPRINT/DIAMETER-VALUE, %MFG_NOMINAL_DIAM
Syntaxes of NC Commands
NC command syntaxes that are supported in the current version are as
follows:
NC Commands for Start Comments
NC_xxx_MO_START_COMMENT syntaxes allow an
automatic output in the APT of instructions at the start of machining operations,
which allows among other things to easily recognize the start of an operation,
to know the type of the operation, or to launch functions automatically
(start coolant, axis unlocking, activating a working mode, and so on).
A sample PP Table (PPTableSampleMOComment.pptable) is delivered in the ..\startup\manufacturing\PPTables
folder.
For axial machining operations:
*START_NC_INSTRUCTION NC_AXIAL_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_AXIAL_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT PATTERN NAME = %MFG_PATTERN_NAME
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_AXIAL_MO_START_COMMENT END
*END
*END
The following example shows the type of APT source that can be generated:
PPRINT NC_AXIAL_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = Drilling
PPRINT OPERATION NAME = Drilling.1
PPRINT PATTERN NAME = Hole.1
PPRINT TOOL ASSEMBLY = Drill_Diam10
PPRINT NC_AXIAL_MO_START_COMMENT END
PPRINT OPERATION NAME : Drilling.1
$$ Start generation of : Drilling.1
LOADTL/2,1
SPINDL/ 204.0000,SFM,CLW
RAPID
GOTO / 130.00000, -55.00000, 2.50000
CYCLE/DRILL, 52.886751, 2.500000, 0.200000,MMPR
GOTO / 130.00000, -55.00000, 0.00000
CYCLE/OFF
For 3-axis milling operations:
*START_NC_INSTRUCTION NC_3X_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_3X_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_3X_MO_START_COMMENT END
*END
*END
For 5-axis milling operations:
*START_NC_INSTRUCTION NC_5X_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_5X_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_5X_MO_START_COMMENT END
*END
*END
For turning operations:
*START_NC_INSTRUCTION NC_LATHE_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_LATHE_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_LATHE_MO_START_COMMENT END
*END
*END
For 2.5-axis milling operations:
*START_NC_INSTRUCTION NC_MILL_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_MILL_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_MILL_MO_START_COMMENT END
*END
*END
NC Commands for End Comments
NC_xxx_MO_END_COMMENT syntaxes allow an automatic
output in the APT of instructions at the end of machining operations (stop
spindle rotation, stop coolant, axis locking / unlocking, deactivating a
working mode, and so on) and to easily recognize the end of operations.
This allows the PP to stop reading ahead of the APT if it is searching an
instruction only inside the current operation, for example. This avoids
the need to manually insert APT words, which is not always possible.
For axial machining operations:
*START_NC_INSTRUCTION NC_AXIAL_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_AXIAL_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT PATTERN NAME = %MFG_PATTERN_NAME
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_AXIAL_MO_END_COMMENT END
*END
*END
The following example shows the type of APT source that can be generated:
$$ End generation of : Drilling.1
PPRINT NC_AXIAL_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = Drilling
PPRINT OPERATION NAME = Drilling.1
PPRINT PATTERN NAME = Hole.1
PPRINT TOOL ASSEMBLY = Drill_Diam10
PPRINT NC_AXIAL_MO_END_COMMENT END
PPRINT OPERATION NAME : Drilling.1
For 3-axis milling operations:
*START_NC_INSTRUCTION NC_3X_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_3X_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_3X_MO_END_COMMENT END
*END
*END
For 5-axis milling operations:
*START_NC_INSTRUCTION NC_5X_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_5X_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_5X_MO_END_COMMENT END
*END
*END
For turning operations:
*START_NC_INSTRUCTION NC_LATHE_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_LATHE_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_LATHE_MO_END_COMMENT END
*END
*END
For 2.5-axis milling operations:
*START_NC_INSTRUCTION NC_MILL_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_MILL_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_MILL_MO_END_COMMENT END
*END
*END
Other NC Commands
Parameters listed under a context have to be used in the same context
(where it makes sense) and should not be extended to other contexts.
NC_AXIS_LOCK
Allows blocking a linear or rotary axis.
See Displacing and Locking Linear and Rotary Axes
for more information.
MFG_AXIS_LOCK_STATUS:lock status of NC axis
MFG_NCAXIS_NAME:name of NC axis
NC_AXIS_MOVE
Allows linear displacement.
See Displacing and Locking Linear and Rotary Axes
for more information.
MFG_NCAXIS_NAME: name of NC axis
MFG_AXIS_POSITION: position if NC axis
NC_CHANGE_REF_PT
Allows selecting the tool compensation corresponding to the desired tool
output point.
MFG_QUADRANT: Number of the compensation type (for example, 2 for compensation
type P2)
MFG_TL_SET_X: Tool assembly set length in x direction
MFG_TL_SET_Y: Tool assembly set length in y direction
MFG_TL_SET_Z: Tool assembly set length in z direction
MFG_NOSE_RADIUS: Insert nose radius
MFG_CMP_TL_SET_X: Computed Tool Assembly set length in X direction
MFG_CMP_TL_SET_Y: Computed Tool Assembly set length in Y direction
MFG_CMP_TL_SET_Z: Computed Tool Assembly set length in Z direction
MFG_CMP_NOSE_RADIUS: Nose radius corresponding to the active compensation
point (left or right). Nose radius could be different for groove insert
(left radius, right radius), when changing the active compensation point
automatically. For other inserts (diamond, square, and so on) the value
is the insert radius.
MFG_LGTH_COR_REG, MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): number
of the correction register.
Default syntax: SWITCH/%MFG_QUADRANT
Syntax example for turning operations:
SWITCH/%MFG_TL_COMP,%MFG_QUADRANT,INCR,%MFG_TL_SET_X,%MFG_TL_SET_Z,%MFG_NOSE_RADIUS
NC_COMMENT
MFG_MO_COMMENT: comment defined on machining operation.
Default syntax: %MFG_MO_COMMENT
NC_COMPENSATION
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): value of the tool compensation
length
MFG_TL_COMP_RAD: value of the tool compensation radius
MFG_TL_NUMBER: tool number associated to the compensation
MFG_TL_NAME: name of tool associated to the compensation.
Default syntax: LOADTL/%MFG_TL_NUMBER,%MFG_TL_COMP
NC_CUTCOM_ON
The syntax of this NC command is CUTCOM/ON and cannot be parameterized.
NC_CUTCOM_OFF
The syntax of this NC command is CUTCOM/OFF and cannot be parameterized.
NC_CUTCOM_NORMDS_ON
The syntax of this NC command is CUTCOM/SAME, NORMDS and cannot be parameterized.
NC_CUTCOM_NORMDS_OFF
The syntax of this NC command is CUTCOM/OFF and cannot be parameterized.
NC_CUTCOM_NORMPS_ON
The syntax of this NC command is CUTCOM/NORMPS and cannot be parameterized.
NC_CUTCOM_NORMPS_OFF
The syntax of this NC command is CUTCOM/OFF and cannot be parameterized.
NC_CUTCOM_LEFT
The syntax of this NC command is CUTCOM/LEFT and cannot be parameterized.
NC_CUTCOM_RIGHT
The syntax of this NC command is CUTCOM/RIGHT and cannot be parameterized.
NC_DELAY
MFG_DELAY_UNIT: list with two values defining the delay units.
First value: delay expressed in number of revolutions.
REV is the default value.
Second value: delay expressed in seconds.
A blank string (represented by 8 underscore characters) is the default value.
When the statement is generated by the application this string is ignored.
MFG_DELAY_VALUE: numerical value of the delay.
Default syntax: DELAY/%MFG_DELAY_VALUE,&MFG_DELAY_UNIT
NC_FEEDRATE
MFG_FEED_UNIT: list with two values defining the feedrate units.
First value: feedrate expressed in model units per minute. MMPM is the default
value.
Second value: feedrate expressed in model units per revolution. MMPR is
the default value.
MFG_FEED_VALUE: numerical value of the feedrate.
Default syntax: FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
NC_HELICAL_INTERPOLATION
%MFG_HELICAL_X_CENTER: X coordinate of the helix center (output in the
current machining axis);
this point is defined on the plane perpendicular to the helix axis and includes
the helix start point.
%MFG_HELICAL_Y_CENTER: Y coordinate of the helix center (output in the current
machining axis);
this point is defined on the plane perpendicular to the helix axis and includes
the helix start point.
%MFG_HELICAL_Z_CENTER: Z coordinate of the helix center (output in the current
machining axis);
this point is defined on the plane perpendicular to the helix axis and includes
the helix start point.
%MFG_HELICAL_INDIRV_I: I component of the tangent at the helix start point
%MFG_HELICAL_INDIRV_J: J component of the tangent at the helix start point
%MFG_HELICAL_INDIRV_K: K component of the tangent at the helix start point
%MFG_HELICAL_I_AXIS: I component of helix axis
%MFG_HELICAL_J_AXIS: J component of helix axis
%MFG_HELICAL_K_AXIS: K component of helix axis
%MFG_HELICAL_PITCH: helix pitch
%MFG_HELICAL_RADIUS: helix radius
%MFG_HELICAL_ X_END: X coordinate of the helix end point (output in the
current machining axis)
%MFG_HELICAL_ Y_END: Y coordinate of the helix end point (output in the
current machining axis)
%MFG_HELICAL_ Z_END: Z coordinate of the helix end point (output in the
current machining axis)
%MFG_HELICAL_ANGLE: helix angle
%MFG_HELICAL_HEIGHT: helix height
%MFG_HELICAL_ROUND: number of turns of the helix
Default syntax, which is defined with required parameters only:
HELICAL/, %MFG_HELICAL_ X_CENTER, %MFG_HELICAL_Y_CENTER, %MFG_HELICAL_ Z_CENTER,
%MFG_HELICAL_INDIRV_I, %%MFG_HELICAL_INDIRV_J, %MFG_HELICAL_INDIRV_K,
%MFG_HELICAL_I_AXIS, %MFG_HELICAL_J_AXIS, %MFG_HELICAL_K_AXIS, %MFG_HELICAL_PITCH,
%MFG_HELICAL_RADIUS, %MFG_HELICAL_ X_END, %MFG_HELICAL_ Y_END, %MFG_HELICAL_
Z_END
NC_MACHINING_AXIS
The syntax of this NC command is as follows:
$$*CATIA0
$$ %MFG_NCAXIS_IDENTIFIER
$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ %MFG_NCAXIS_X_ORIG
$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ %MFG_NCAXIS_Y_ORIG
$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ %MFG_NCAXIS_Z_ORIG
The syntax of this NC command for a multi-slide lathe machine environment
is as follows:
$$*CATIA0
$$ %MFG_NCAXIS_IDENTIFIER, %MFG_SPINDLE_NAME, %MFG_SPINDLE_NUMBER
$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ %MFG_NCAXIS_X_ORIG
$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ %MFG_NCAXIS_Y_ORIG
$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ %MFG_NCAXIS_Z_ORIG
The parameters are as follows:
MFG_NCAXIS_IDENTIFIER: manufacturing program name for the first output,
otherwise name of the machining axis change
MFG_SPINDLE_NAME: name of the spindle that is linked to the origin
MFG_SPINDLE_NUMBER: number of the spindle that is linked to the origin
MFG_NCAXIS_X_ORIG, MFG_NCAXIS_Y_ORIG, MFG_NCAXIS_Z_ORIG: coordinates of
the machining axis origin
MFG_NCAXIS_X_VECX, MFG_NCAXIS_Y_VECX, MFG_NCAXIS_Z_VECX: components of the
x-axis
MFG_NCAXIS_X_VECY, MFG_NCAXIS_Y_VECY, MFG_NCAXIS_Z_VECY: components of the
y-axis
MFG_NCAXIS_X_VECZ, MFG_NCAXIS_Y_VECZ, MFG_NCAXIS_Z_VECZ: components of the
z-axis.
See Displacing and Locking Linear and Rotary
Axes for more information.
NC_MILL_TURRET_INVERSION
The syntax of this NC command is as follows:
*START_NC_COMMAND NC_MILL_TURRET_INVERSION
*START_SEQUENCE
ROTATE/CAXIS,%MFG_MILL_TURRET_AXIS_INVERT
*END
*END
Parameter is the following:
%MFG_MILL_TURRET_AXIS_INVERT: value of this parameter indicates whether
the mill turret is at inverted position or not
Possible values:
0: not inverted (C-axis = 0 degree)
1: inverted (C-axis = 180 degrees)
Notes:
- The syntax is output only when the operation is performed on
a machine with a turret defined as a Mill Turret (for example, on
a multi-slide lathe machine).
- If no syntax is defined in the PP word table, no statement is
generated on turning operation.
NC_MILL_TURRET_ORIENTATION
The syntax of this NC command is as follows:
*START_NC_COMMAND NC_MILL_TURRET_ORIENTATION
BAXIS,/%MFG_MILL_TURRET_I_AXIS, %MFG_MILL_TURRET_J_AXIS, MFG_MILL_TURRET_K_AXIS
*END
Parameters are the following:
% MFG_MILL_TURRET_I_AXIS: I component of tool axis orientation
% MFG_MILL_TURRET_J_AXIS: J component of tool axis orientation
% MFG_MILL_TURRET_K_AXIS: K component of tool axis orientation
Coordinates are defined in the machining axis (spindle axis system).
NC_MULTAX_ON
The syntax of this NC command is MULTAX and cannot be parameterized.
NC_MULTAX_OFF
The syntax of this NC command is MULTAX/OFF and cannot be parameterized.
NC_PITCH
MFG_THREAD_PITCH: Thread pitch
MFG_NUM_THREADS: Number of threads.
Syntax examples:
PITCH/%MFG_THREAD_PITCH
PITCH/(1/%MFG_THREAD_PITCH),MULTRD,%MFG_NUM_THREADS
FEDRAT/%MFG_THREAD_PITCH,MMPR
NC_SPINDLE_ON
The syntax of this NC command is SPINDL/ON and cannot be parameterized.
NC_SPINDLE_START or
NC_SPINDLE
MFG_SPNDL_UNIT: list with two values defining the spindle rotation units.
First value: spindle rotation expressed in revolutions per minute. RPM is
the default value.
Second value: spindle rotation expressed in surface meters per minute. SMM
is the default value.
MFG_SPNDL_WAY: list with two values defining the direction of rotation of
the spindle.
First value: spindle rotation processed clockwise. CLW is the default value.
Second value: spindle rotation processed counter-clockwise. CCLW is the
default value.
MFG_SPNDL_SPEED: numerical value of the spindle speed.
MFG_SPNDL_DIAMTR: diameter of the tool where the spindle speed is taken
into account.
Default syntax: SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
NC_SPINDLE_LATHE
Note that this corresponds to the part's spindle speed.
MFG_SPNDL_UNIT: list with two values defining the spindle rotation units.
First value: spindle rotation expressed in revolutions per minute. RPM is
the default value.
Second value: spindle rotation expressed in surface meters per minute. SMM
is the default value.
MFG_SPNDL_WAY: list with two values defining the direction of rotation of
the spindle.
First value: spindle rotation processed clockwise. CLW is the default value.
Second value: spindle rotation processed counter-clockwise. CCLW is the
default value.
MFG_SPNDL_SPEED: numerical value of the spindle speed.
Default syntax: SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
NC_SPINDLE_STOP
This NC command ensures compatibility with V4. You should use NC_SPINDLE_LOCK
or NC_SPINDLE_OFF, if possible.
MFG_SPNDL_STOP: list with two values defining the action applied to the
spindle.
First value: de-activation of the spindle. OFF is the default value.
Second value: spindle locked in an indexed position. LOCK is the default
value.
NC_SPINDLE_LOCK
The syntax of this NC command is SPINDL/LOCK and cannot be parameterized.
NC_SPINDLE_MAXSPEED
Note that this corresponds to the maximum spindle speed defined on the
operation.
MFG_MAX_ SPNDL_SPEED: numerical value of the maximum spindle speed.
MFG_MAX_SPNDL_UNIT: the rotation units of the maximum spindle speed are
in revolutions per minute (RPM).
MFG_SPNDL_WAY: list with two values defining the direction of rotation of
the spindle.
First value: spindle rotation processed clockwise. CLW is the default value.
Second value: spindle rotation processed counter-clockwise. CCLW is the
default value.
Default syntax: MAXSPNDL/%MFG_MAX_SPNDL_SPEED, &MFG_MAX_SPNDL_UNIT
Example:
*START_NC_COMMAND NC_SPINDLE_MAXSPEED
MAXSPNDL/%MFG_MAX_SPNDL_SPEED, & MFG_MAX_SPNDL_UNIT, & MFG_SPNDL_WAY
*END
NC_SPINDLE_OFF
The syntax of this NC command is SPINDL/OFF and cannot be parameterized.
NC_THREAD_TURN
Syntax example: THREAD/TURN
NC_THREAD_TURN_OFF
Ends a NC_THREAD_TURN statement.
Syntax example:
*START_NC_COMMAND
NC_THREAD_TURN_OFF
THREAD/OFF
*END
NC Instructions
You can define for a given machine tool (i.e. post-processor) sequences
of PP word syntaxes associated to particular NC instructions.
NC instructions are either auxiliary commands
or axial machining operations.
A syntax comprises a major word and one or more syntax elements such
as minor words, numerical values and standard parameters. A set of standard
parameters is associated to each NC instruction. Parameters may be combined
in arithmetical expressions.
A syntax that includes parameters is a parameterized syntax (see
examples below):
*START_NC_INSTRUCTION NC_TOOL_CHANGE
*START_SEQUENCE
TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM
TPRINT/%MFG_TOOL_NAME
LOADTL/%MFG_TOOL_NUMBER
*END
*END
*START_NC_INSTRUCTION NC_TAPPING
*START_SEQUENCE
CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
*END
*END
Note that the % character indicates a parameter.
You can define one or more syntax sequences for each NC instruction.
For an example of how to define syntax sequences in NC Instructions,
please see PP Word Syntaxes in the Customizing
section of this guide.
Standard Parameters for Auxiliary Command
Type NC Instructions
These parameters include data that is defined on the corresponding entity
or parameters that are computed according to an application method.
Auxiliary command type NC Instructions are as follows:
NC_ACTIVITY_HEADER
This instruction is used to valuate parameters
of an activity during the generation of APT.
Default syntax (empty):
*START_NC_INSTRUCTION
NC_ACTIVITY_HEADER
*START_SEQUENCE
*END
*END
Syntax example:
$$ OPERATION NAME = %MFG_MO_IDENTIFIER
The CYCLE instruction is generated by
drilling and probing operations.
A specific NC_CYCLE_OFF instruction is
associated to the drilling, lathe and probing
operations:
- For a drilling operation:
*START_NC_INSTRUCTION
NC_AXIAL_CYCLE_OFF
*START_SEQUENCE
CYCLE/OFF
*END
*END
- For a lathe operation:
*START_NC_INSTRUCTION
NC_LATHE_CYCLE_OFF
*START_SEQUENCE
CYCLE/OFF
*END
*END
- For a probing operation:
*START_NC_INSTRUCTION
NC_PROBING_CYCLE_OFF
*START_SEQUENCE
CYCLE/OFF
*END
*END
The instruction is managed
automatically by the operation, not by the user.
For existing tool paths, if you had
defined the NC_CYCLE_OFF in your PPTable, define
NC_AXIAL_CYCLE_OFF, NC_LATHE_CYCLE_OFF and
NC_PROBING_CYCLE_OFF as NC_CYCLE_OFF to keep the
same tool path.
NC_END_MACRO
MFG_IDENTIFIER: Part Operation identifier
MFG_MACHINE_NAME: Machine name.
Default syntax: SPINDL/OFF
MFG_TYPE_OF_ROT: Rotation type (absolute angle
in this version)
MFG_DIR_OF_ROT: Rotation direction (clockwise or
counterclockwise)
MFG_AMOUNT_ROT: Angle of rotation about the axis
of rotation
MFG_AXIS_OF_ROT: Axis of rotation on machine head.
MFG_ABC_AXIS: Axis of rotation on machine head to
get Minor word AAXIS, BAXIS or CAXIS.
See Displacing and Locking
Linear and Rotary Axes for more information.
Default syntax: ROTHED/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT
NC_ORIGIN
MFG_NCAXIS_X_ORIG, MFG_NCAXIS_Y_ORIG, MFG_NCAXIS_Z_ORIG:
coordinates of the origin
MFG_ORIGIN_NUMBER: origin number
MFG_ORIGIN_GROUP: origin group.
Default syntax: ORIGIN/%MFG_NCAXIS_X_ORIG,%MFG_NCAXIS_Y_ORIG,%MFG_NCAXIS_Z_ORIG,$
%MFG_ORIGIN_NUMBER,%MFG_ORIGIN_GROUP
NC_PROGRAM_HEADER
MFG_PROGRAM_NAME: Manufacturing Program name
MFG_CHANNEL_NUMBER: Channel number (Turret).
Default syntax (empty):
*START_NC_INSTRUCTION
NC_PROGRAM_HEADER
*START_SEQUENCE
*END
*END
Syntax example:
PROG_NAME,%MFG_PROGRAM_NAME
Syntax example in a Multi-Axis Lathe machine
environment:
CHANNEL,%MFG_CHANNEL_NUMBER
NC_START_MACRO
MFG_IDENTIFIER: Part Operation identifier
MFG_PROGRAM_NAME: Manufacturing Program name
MFG_MACHINE_NAME: Machine name
MFG_MODEL_NAME: Name of the CATProcess (with document
suffix)
MFG_PRODUCT_NAME: Name of the CATProduct/CATPart
(with no document suffix).
Default syntax: PARTNO PART TO BE
MACHINED
Note: When PARTNO is defined as a major word
with text, if you want to use PARTNO with parameters
for a clfile output, the "/" character must be replaced
by a space.
You can use the "/" character for an APT output.
MFG_TYPE_OF_ROT: Rotation type (absolute angle
in this version)
MFG_DIR_OF_ROT: Rotation direction (clockwise or
counterclockwise)
MFG_AMOUNT_ROT: Angle of rotation about the axis
of rotation
MFG_AXIS_OF_ROT: Axis of rotation on machine table.
MFG_ABC_AXIS: Axis of rotation on machine table
to get Minor word AAXIS, BAXIS or CAXIS.
Default syntax: ROTABL/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT
See Displacing and Locking
Linear and Rotary Axes for more information.
Please note that if tool assembly resources are
not used in your process, the term 'tool assembly'
means 'tool' or 'cutter' in the following description.
MFG_TL_ASMBLY_ID: Tool assembly identifier
MFG_TL_SET_LGTH: Tool set length
MFG_NOMINAL_DIAM: Nominal diameter of the tool
MFG_TOOL_COMMENT: Comment associated with the tool
MFG_TOOL_NUMBER: Tool assembly number
MFG_ASS_COMMENT: Comment associated with the tool
assembly
MFG_WEIGHT_SNTX: Tool weight syntax
MFG_COOLNT_SNTX: Coolant supply syntax
MFG_TOOTH_DES: Tooth description
MFG_DIAMETER_2: Diameter 2 of the tool assembly
MFG_MAX_MIL_TIME: Tool life (in time units)
MFG_MAX_MIL_LGTH: Tool life (in length units)
MFG_CORNER_RAD: Tool corner radius
MFG_CUT_ANGLE: Tool cutting angle
MFG_LENGTH: Length of active part of the tool
MFG_TL_TIP_LGTH: Tool tip length
MFG_CUT_LENGTH: Tool cutting length
MFG_NB_OF_FLUTES: Number of teeth
MFG_TOOL_NAME: Tool name
MFG_TL_SET_X: Tool set length in x direction
MFG_TL_SET_Y: Tool set length in y direction
MFG_WAY_OF_ROT: Computed rotation direction of tool
(RIGHTHAND or LEFTHAND)
MFG_TOOL_ASS_POW: Computed tool assembly power type
If fixed the value is TURN, otherwise the value
is MILL
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4):
value of the tool compensation length
MFG_TOOL_COMP_2: value of the second tool compensation
length
MFG_FEED_MACH: Machining feedrate (*)
MFG_SPNDL_MACH: Machining spindle speed (*)
MFG_FEED_UNIT: Computed feedrate unit (*)
MFG_SPNDL_UNIT: Computed spindle speed unit (*)
(*) The values of these feed and speed
attributes are taken from the first machining operation
under the tool change.
Default syntax: TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM
|
|
MFG_TL_ASMBLY_ID: Tool assembly identifier
MFG_ASS_COMMENT: Comment associated with the tool
assembly
MFG_TOOL_NUMBER: Tool assembly number
MFG_TOOL_NAME: Insert-holder name
MFG_TOOL_COMMENT: Comment associated with the insert-holder
MFG_INSERT_NAME: Insert name
MFG_INSERT_COMMENT: Comment associated with the
insert
MFG_QUADRANT: Number of the compensation type (for
example, 2 for compensation type P2)
MFG_TL_SETUP_ANG: Tool assembly setup angle (value
in degrees)
MFG_TL_SET_X: Tool assembly set length in x direction
MFG_TL_SET_Y: Tool assembly set length in y direction
MFG_TL_SET_Z: Tool assembly set length in z direction
MFG_NOSE_RADIUS: Insert nose radius
MFG_CMP_TL_SET_X: Computed Tool Assembly set length
in X direction
MFG_CMP_TL_SET_Y: Computed Tool Assembly set length
in Y direction
MFG_CMP_TL_SET_Z: Computed Tool Assembly set length
in Z direction
MFG_CMP_NOSE_RADIUS: Nose radius corresponding to
the active compensation point (left or right). Nose
radius could be different for groove insert (left
radius, right radius), when changing the active
compensation point automatically. For other inserts
(diamond, square, and so on) the value is the insert
radius.
MFG_HAND_STYLE: Insert-holder style (LEFT_HAND,
RIGHT_HAND or NEUTRAL)
MFG_TOOL_INVERT: Tool assembly inversion. Defines
if the insert-holder has been inverted with respect
to the original insert-holder style. Possible values
are 0 (not inverted) or 1 (inverted).
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4):
Value of the insert-holder compensation length
MFG_LIFE_TIME: Insert life-time (in time units).
Not available for Groove inserts.
MFG_CLEAR_ANGLE: Insert clearance angle
MFG_INSERT_LGTH: Insert length
MFG_INSCRIB_DIAM: Inscribed diameter of insert
MFG_INSERT_ANGLE: Insert shape angle
MFG_SPNDL_WAY: Spindle direction
MFG_FEED_MACH: Machining feedrate (*)
MFG_FEED_UNIT: Feedrate unit (*)
MFG_SPNDL_MACH: Machining spindle speed (*)
MFG_SPNDL_UNIT: Spindle speed unit (*).
(*) The values of these feed and speed
attributes are taken from the first machining operation
under the tool change.
Default syntax: TOOLNO/%MFG_TOOL_NUMBER,TURN
Mill/Turn integration and the NC_TOOL_CHANGE_LATHE
instruction
For a drilling operation using a non-powered
Milling Tool Assembly and machining along the spindle
axis, a Lathe Tool Change is created. In this case,
the following Insert attributes are replaced by
Tool attributes:
|
Insert attributes
MFG_NOSE_RADIUS
MFG_INSCRIB_DIAM
MFG_LIFE_TIME
MFG_LIFE_LGTH
MFG_INSERT_LGTH
MFG_CLEAR_ANGLE
MFG_INSERT_ANGLE |
|
Tool attributes
MFG_NOMINAL_DIAM
MFG_NOMINAL_DIAM
MFG_MAX_MIL_TIME
MFG_MAX_MIL_LGTH
MFG_CUT_LENGTH
0 (not valuated)
MFG_CUT_ANGLE |
Displacing and Locking Linear and Rotary
Axes
Machine instructions have a customizable format in the PP table.
They can contain the following information.
Linear displacements:
Default format for a linear displacement:
PPFUN/ <Letter of the axis>,<Letter of the axis>AXIS,value
of the displacement
Otherwise, it can be customized in the PP table by means of NC_AXIS_MOVE.
/
*START_NC_COMMAND NC_AXIS_MOVE
CLAMP/OFF,%MFG_NCAXIS_NAME,%MFG_AXIS_POSITION
*END
/
Rotary displacements:
Format for a rotary displacement:
ROTABL/value of the rotation,<rotary direction >,<rotation
axis>
Otherwise, it can be customized in the PP table by means of the NC instructions
NC_TABLE_ROTATION, NC_MACHINING_AXIS and NC_HEAD_ROTATION.
/
*START_NC_INSTRUCTION NC_HEAD_ROTATION
*START_SEQUENCE
ROTHED/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT
*END
*END
/
*START_NC_INSTRUCTION NC_TABLE_ROTATION
*START_SEQUENCE
ROTABL/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT,%MFG_ABC_AXIS
*END
*END
/
*START_NC_INSTRUCTION NC_MACHINING_AXIS
*START_SEQUENCE
$$ %MFG_NCAXIS_IDENTIFIER
$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ %MFG_NCAXIS_X_ORIG
$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ %MFG_NCAXIS_Y_ORIG
$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ %MFG_NCAXIS_Z_ORIG
CATMAT/%MFG_NCAXIS_X_ORIG,%MFG_NCAXIS_Y_ORIG,%MFG_NCAXIS_Z_ORIG,%MFG_NCAXIS_X_VECX,%MFG_NCAXIS_X_VECY,%MFG_NCAXIS_X_VECZ,%MFG_NCAXIS_Y_VECX,%MFG_NCAXIS_Y_VECY,%MFG_NCAXIS_Y_VECZ,%MFG_NCAXIS_Z_VECX,%MFG_NCAXIS_Z_VECY,%MFG_NCAXIS_Z_VECZ,%MFG_NCAXIS_IDENTIFIER
*END
*END
To block a linear or rotary axis:
If the axis is blocked:
LOCK/ <Letter of the axis>,<Letter of the axis>AXIS,ON
Otherwise, it can be customized in the PP table by means of NC_AXIS_LOCK
/
*START_NC_COMMAND NC_AXIS_LOCK
CLAMP/%MFG_AXIS_LOCK_STATUS,%MFG_NCAXIS_NAME
*END
/
Standard Parameters for Axial Machining
Operation Type NC Instructions
For axial machining operations, the standard parameters are either:
- parameters defined on the corresponding machining operation
(geometrical data, machining strategy parameters, feeds and speeds,
and so on)
- parameters that are calculated according to an application method.
In the figures below:
- detail depth (MFG_DETAIL_DEPTH), total depth (MFG_TOTAL_DEPTH)
and total depth up to the tool compensation point (MFG_TOTAL_DEPTH_COMP)
are computed parameters
- breakthrough distance (MFG_BREAKTHROUGH) is a machining strategy
parameter
- tool tip length is a geometric attribute of the tool (MFG_TL_TIP_LGTH).
Overall breakthrough is the breakthrough distance plus the tool tip length.
 |
|
Figure 1.
Total depth without breakthrough
|
 |
|
Figure 2.
Total depth with breakthrough
|
The figures below show Depth mode behavior on axial operations with chamfering
machining:
 |
|
Figure 3.
Spot Drilling with Depth mode=By Tip
|
 |
|
Figure 4.
Countersinking with Depth mode=By Diameter
|
Axial machining operation type NC Instructions are as follows:
|
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_CLEAR_TIP_2: Second approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_LIFT_MODE: Shift mode (0: None / 1: Linear coordinates
/ 2: Polar coordinates)
MFG_XOFF: Shift along X
MFG_YOFF: Shift along Y
MFG_ZOFF: Shift along Z
MFG_LIFT_ANGLE: Shift angle
MFG_LIFT_DIST: Shift distance
MFG_RETRACT_CLEAR_TIP: retract clearance
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length
number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_BCK_BORE_VAL: Back bore depth
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
MFG_CMP_OFFSET: Computed offset
MFG_CMP_ANGLE: Computed angle. This parameter is computed
if Shift mode is set to 'Linear coordinates'. Otherwise,
the Shift angle is returned as is.
Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length
number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_LIFT_MODE: Shift mode (0: None / 1: Linear coordinates
/ 2: Polar coordinates)
MFG_XOFF: Shift along X
MFG_YOFF: Shift along Y
MFG_ZOFF: Shift along Z
MFG_LIFT_ANGLE: Shift angle
MFG_LIFT_DIST: Shift distance
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip.
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
MFG_CMP_OFFSET: Computed offset
MFG_CMP_ANGLE: Computed angle. This parameter is computed
if Shift mode is set to 'Linear coordinates'. Otherwise,
the Shift angle is returned as is.
Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_CHAMFER_FEED_VALUE and MFG_CHAMFER_FEED (compatibility
V4): Machining feedrate for chamfering phase
MFG_CHAMFER_SPINDLE_VALUE: Machining spindle speed for chamfering
phase.
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_CLEAR_TIP_2: Second approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length
number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_2: Length number of second corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
MFG_TOOL_COMP_DIST_2: Distance between the position of the
second corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER and MFG_CHAMFER_VAL (compatibility V4):
Chamfer diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance.
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_AXIAL_DEPTH: Maximum depth of cut
MFG_OFFSET_RET: Retract offset
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Tool nominal diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
MFG_EFFCT_DEPTH: Effective depth (= maximum depth of cut)
Default syntax: CYCLE/BRKCHP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility
V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_RADIAL_STEP: Distance between paths
MFG_RADIAL_NB: Number of paths
MFG_AXIAL_STRAT: Axial mode (1: Max depth of cut / 2: Number
of levels / 3: Number of levels without top)
MFG_AXIAL_DEPTH: Maximum depth of cut
MFG_AXIAL_NUMBER: Number of levels
MFG_SEQUENCING_STRAT: Sequencing mode (1: Radial first /
2: Axial first)
MFG_TOLER_MACH: Machining tolerance
MFG_DIR_CUT: Direction of cut (1: Climb / 2: Conventional)
MFG_OVERHANG: Percentage overlap
MFG_DRAFT_ANGLE: Automatic draft angle
MFG_CIRCULAR_MODE: Machining mode (1: Standard / 2: Helical)
MFG_HELIX_MODE: Helix mode (1: By pitch / 2: By angle)
MFG_HELIX_ANGLE: Helix angle
MFG_PITCH: Helix pitch
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of hole (offset on contour
is taken into account in this value)
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
Default syntax: CYCLE/CIRCULARMILLING,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
|
|
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (3: Diameter / 4: Distance).
See Figure 4 above.
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter).
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Countersink diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 4 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth and breakthrough.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/CSINK,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3:
Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_AXIAL_DEPTH: Maximum depth of cut
MFG_OFFSET_RET: Retract offset
MFG_DEPTH_DEC: Decrement rate
MFG_DEPTH_LIM: Decrement limit
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
MFG_EFFCT_DEPTH: Effective depth (= Maximum depth of cut)
Default syntax: CYCLE/DEEPHL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3:
Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP,%MFG_FEED_MACH,&MFG_FEED_UNIT
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
|
|
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier.
Machining Strategy parameters are as follows:
MFG_THREAD_MACHINING: Machining type (1: Constant depth
/ 2: Section of cut)
MFG_THREAD_PENETRATION: Penetration (1: Straight / 2: Flank
/ 3: Alternate)
MFG_THREAD_UNIT: Unit (1: Pitch / 2: Thread per inch)
MFG_THREAD_PROFILE: Profile (1: ISO / 2: Trapezoidal / 3:
UNC / 4: Gaz)
MFG_THREAD_ORIENTATION: Orientation (1: Internal / 2: External)
MFG_THREAD_PITCH: Thread pitch
MFG_NUM_THREADS: Number of threads
MFG_THRD_PER_UNIT: Threads per inch
MFG_FIR_PATH: Boolean for first passes (0: No /
1: Yes)
MFG_LAS_PATH: Boolean for last passes (0: No / 1: Yes)
MFG_SPR_PATH: Boolean for spring passes (0: No / 1: Yes)
MFG_NUM_FIR_PATH: Number of first passes
MFG_NUM_LAS_PATH: Number of last passes
MFG_NUM_SPR_PATH: Number of spring passes
MFG_FIR_SECT_CUT: Section of cut for first passes
MFG_LAS_DEPT_CUT: Depth of cut for last passes
MFG_FIR_SECT_RAT: Section ratio between first passes
and next passes
MFG_CRES_DIA_CLR: Clearance on crest diameter
MFG_ENTER_ANG: Entry angle
MFG_LEAD_IN_DIST: Lead-in distance
MFG_LIFT_OFF_ANG: Lift-off angle
MFG_LIFT_OFF_DIS: Lift-off distance
MFG_SPNDL_UNIT: list with two values defining the spindle
rotation units.
First value: spindle rotation expressed in revolutions per
minute. RPM is the default value.
Second value: spindle rotation expressed in surface meters
per minute. SMM is the default value.
MFG_SPNDL_WAY: list with two values defining the direction
of rotation of the spindle.
First value: spindle rotation processed clockwise. CLW is
the default value.
Second value: spindle rotation processed counter-clockwise.
CCLW is the default value.
MFG_SPNDL_SPEED: numerical value of the spindle speed.
Computed parameters are as follows:
MFG_ST_THRD_AX: Axial coordinate of the start thread
on the crest.
MFG_ST_THRD_RAD: Radial coordinate of the start thread
on the crest.
MFG_END_THRD_AX: Axial coordinate of the end thread
on the crest.
MFG_END_THRD_RAD: Radial coordinate of the end thread
on the crest.
MFG_END_THRD1_AX: Axial coordinate of the end thread
on the root.
MFG_END_THRD1_RAD: Radial coordinate of the end thread
on the root.
MFG_THRD_DEL_RAD: Depth of thread according to the radial
axis.
MFG_THRD_ANG: Angle of the thread. If different from
zero, this angle indicates a conical thread.
MFG_NOM_DIAM: Nominal diameter of the thread.
MFG_THRD_LENGTH: Length of the thread.
MFG_NB_PATH: Number of passes. First, last and spring
passes are not included.
MFG_DEPTH_CUT: Depth of cut.
MFG_SECTION_CUT: Section of cut for passes that follow
the first passes.
MFG_THREAD_DEPTH: Depth of thread.
Default syntax: CYCLE/THREAD,%MFG_THREAD_PITCH
|
|
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/REAM,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Internal diameter of the tool
MFG_THREAD_DIAMETER: Nominal diameter of the tool
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: This parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_TOOL_PITCH: Pitch value defined on tool.
Default syntax: CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder). See
Figure 3 above.
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter).
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Chamfer diameter
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 3 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth and plunge distance.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip)
MFG_DIR_CUT: Direction of cut (1: Climb / 2: Conventional)
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Slot diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_LENGTH: Slot height (= Tool length, which is read on
tool)
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/TSLOT,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Internal diameter of the tool
MFG_THREAD_DIAMETER: Nominal diameter of the tool
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: This parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_TOOL_PITCH: Pitch value defined on tool
Default syntax: CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_TOOL_COMP and MFG_TL_COMP (compatibility
V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Hole internal diameter
MFG_THREAD_DIAMETER: Tool nominal diameter
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: This parameter returns the plunge distance.
The plunge offset is taken into account in this value.
Default syntax: CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
|
NC_THREAD_MILLING
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility
V4): Approach feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_THREAD_STRATEGY: Thread milling mode (1: Mono-pass
/ 2: Optimized-passes)
MFG_THREAD_DIRECTION: Thread milling direction (1:
Top to bottom / 2: Bottom to top)
MFG_CLEAR_TIP: Approach clearance
MFG_BREAKTHROUGH: Breakthrough distance
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length
number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip.
Geometry parameters are as follows:
MFG_DIAMETER: Hole internal diameter
MFG_THREAD_DIAMETER: Hole nominal diameter
MFG_PITCH: Thread pitch
MFG_PITCH_SENS or MFG_PITCH_WAY_OF_ROT: Thread direction
(1: Left-hand / 2: Right-hand)
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_TOOL_PITCH: Pitch value defined on tool
Default syntax: CYCLE/THREADMILLING,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
General parameters are as follows:
MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.
Feeds and Speeds parameters are as follows:
MFG_FEED_APP_MODE: Approach feedrate mode (0: Value /
1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4):
Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility
V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility
V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4):
Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility
V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility
V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility
V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit
Machining Strategy parameters are as follows:
MFG_CLEAR_TIP: Approach clearance
MFG_CLEAR_TIP_2: Second approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip)
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions
/ 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length
number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_2: Length number of second corrector
MFG_TOOL_COMP_DIST: Distance between the position of the
current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the
first corrector and the tool tip
MFG_TOOL_COMP_DIST_2: Distance between the position of the
second corrector and the tool tip
Geometry parameters are as follows:
MFG_DIAMETER: Chamfer diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance
Computed parameters are as follows (see
Figure 1 and
Figure 2 above):
MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation.
This includes the hole depth, breakthrough, and tool tip
length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation
up to the tool compensation point selected for the operation.
This includes hole depth, breakthrough and tool tip length
up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip
or by Diameter), this parameter returns the plunge distance.
The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of
seconds): this parameter is computed if dwell mode is set
to 'revolutions'. Otherwise, the dwell time is returned
as is.
Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP,%MFG_FEED_MACH,&MFG_FEED_UNIT
|